PLANE RESET
Application
Use the PLANE RESET function to reset all tilt angles and deactivate tilting of the working plane.
Description of function
The PLANE RESET function always executes two partial tasks:
- Reset all tilt angles, regardless of the selected tilt function or the type of angle
The function does not reset any offset values!
- Deactivate tilting of the working plane
- Tip
No other tilting function will carry out this partial task!
Even when programming all angles with the value 0 in any tilting function, tilting of the working plane remains active.
The optional rotary axis positioning allows tilting the rotary axes back to the home position as the third partial task.
Input
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 PLANE RESET TURN MB MAX FMAX |
The NC function includes the following syntax elements:
Syntax element | Meaning |
---|---|
PLANE RESET | Syntax initiator for resetting all tilting angles and for deactivating an active tilting function |
MOVE, TURN or STAY | Type of rotary axis positioning Tip Depending on the selection, the optional syntax elements MB, DIST and F, F AUTO or FMAX can be defined. |
Notes
- Before every program run, ensure that no undesired coordinate transformations are in effect. When needed, tilting of the working plane can also be deactivated manually in the 3-D rotation window.
- The touch probe functions allow you to save the inclined position of the workpiece to the preset table as a 3D basic rotation such as Plane (PL). In the NC program you must then align the workpiece with a tilting function (e.g., with PLANE SPATIAL SPA+0 SPB+0 SPC+0 TURN FMAX). You must not use PLANE RESET for the machining, since the control does not consider the 3D basic rotation for this function.