Departure function DEP PLCT
Application
With the NC function DEP PLCT, the control departs from the contour on a circular path, followed by a tangential straight line to the last contour element.
The coordinates of the end point PN are programmed with polar coordinates.
Related topics
- DEP LCT with Cartesian coordinates
Requirement
- Pole CC
You must define a pole CC before programming with polar coordinates.
Description of function
This NC function encompasses the following steps:
- On a circular path from the last contour point PE to the auxiliary point PH
The auxiliary point PH is determined based on the last contour point PE, the radius R and the end point PN.
- On a straight line from the auxiliary point PH to the end point PN
If you program the Z coordinate in the departure function, then the tool moves simultaneously in three axes from the auxiliary point PH to the end point PN.
Input
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 DEP PLCT PR15 PA-90 R8 | ; Tangentially depart from the contour linearly and circularly |
To navigate to this function:
Insert NC function All functions Path contour Departure functions (DEP) DEP PLCT
The NC function includes the following syntax elements:
Syntax element | Meaning |
---|---|
DEP PLCT | Syntax initiator for a linear and circular departure function tangential to the contour |
PR | Polar coordinate radius Number or numerical parameter Entry: absolute or incremental Optional syntax element |
PA | Polar coordinate angle Number or numerical parameter Entry: absolute or incremental Optional syntax element |
R | Radius Number or numerical parameter |
F, FMAX, FZ, FU, FAUTO | |
M |
Note
The Form column allows toggling between the syntaxes for Cartesian and polar coordinate input.
Example DEP PLCT
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 CC X+50 Y+20 | ; Set the pole |
12 LP PR+30 PA+0 RL F300 | ; Approach the last contour element PE with RL |
13 DEP PLCT PR+50 PA+0 R5 | ; Approach PN; distance PE to PN: R5 |