Tool coordinate system T-CS
Application
In the tool coordinate system T-CS the control implements tool compensations and tool inclinations.
Description of function
Properties of the tool coordinate system T-CS
The tool coordinate system T-CS is a three-dimensional Cartesian coordinate system. Its coordinate origin is the tool tip TIP.
By making entries in the tool management, you can define the tool tip relative to the tool carrier reference point. The machine manufacturer usually defines the tool carrier reference point on the spindle tip.
Use the following tool management parameters to define the tool tip relative to the tool carrier reference point:
- L
- DL
You can use positioning blocks in the input coordinate system I-CS to define the position of the tool and therefore the position of the T-CS.
You can use miscellaneous functions to also program in other reference systems, such as M91 for the machine coordinate system M-CS.
Traversing in the machine coordinate system M-CS with M91
The orientation of the T-CS in most cases is identical to that of the I-CS.
If the following functions are active, the orientation of the T-CS depends on the tool inclination:
- M function M128 (#9 / #4-01-1)
Compensating the tool angle of inclination automatically with M128 (#9 / #4-01-1)
- Function FUNCTION TCPM (#9 / #4-01-1)
Compensating the tool angle of inclination with FUNCTION TCPM (#9 / #4-01-1)
Use the miscellaneous function M128 to define the tool inclination in the machine coordinate system M-CS using axis angles. The effects of the tool inclination depend on the machine kinematics:
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 L X+10 Y+45 A+10 C+0 R0 M128 | ; Straight line with miscellaneous function M128 and axis angles |
You can also define a tool inclination in the working plane coordinate system WPL-CS using spatial angles (e.g., with the FUNCTION TCPM function or a straight line LN).
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 FUNCTION TCPM F TCP AXIS SPAT PATHCTRL AXIS | ; FUNCTION TCPM with spatial angles |
12 L A+0 B+45 C+0 R0 F2500 |
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 LN X+48 Y+102 Z-1.5 NX-0.04658107 NY0.00045007 NZ0.8848844 TX0 TY-0.34090025 TZ0.93600126 R0 M128 | ; Straight line LN with surface normal vector and tool orientation |
Transformations in the tool coordinate system T-CS
The following tool compensations have an effect in the tool coordinate system T-CS:
- Compensation values from the tool management
- Compensation values from the tool call
- Values of the compensation tables *.tco
- 3D tool compensation with surface normal vectors (#9 / #4-01-1)