Example: Presetting at center of a circular segment and on top surface of workpiece

  • Q325 = Polar coordinate angle for touch point 1
  • Q247 = Stepping angle for calculating the touch points 2 to 4
  • Q305 = Write to row number 5 of the preset table
  • Q303 = Write the calculated preset to the preset table
  • Q381 = Also set the preset in the touch probe axis
  • Q365 = Move on circular path between measuring points

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

0 BEGIN PGM 413 MM

1 TOOL CALL "TOUCH_PROBE" Z

2 TCH PROBE 413 PRESET OUTS. CIRCLE ~

Q321=+25

;CENTER IN 1ST AXIS ~

Q322=+25

;CENTER IN 2ND AXIS ~

Q262=+30

;NOMINAL DIAMETER ~

Q325=+90

;STARTING ANGLE ~

Q247=+45

;STEPPING ANGLE ~

Q261=-5

;MEASURING HEIGHT ~

Q320=+2

;SET-UP CLEARANCE ~

Q260=+50

;CLEARANCE HEIGHT ~

Q301=+0

;MOVE TO CLEARANCE ~

Q305=+5

;NUMBER IN TABLE ~

Q331=+0

;PRESET ~

Q332=+10

;PRESET ~

Q303=+1

;MEAS. VALUE TRANSFER ~

Q381=+1

;PROBE IN TS AXIS ~

Q382=+25

;1ST CO. FOR TS AXIS ~

Q383=+25

;2ND CO. FOR TS AXIS ~

Q384=+0

;3RD CO. FOR TS AXIS ~

Q333=+0

;PRESET ~

Q423=+4

;NO. OF PROBE POINTS ~

Q365=+0

;TYPE OF TRAVERSE

3 END PGM 413 MM