Cycle 1282 OCM CIRCLE BOUNDARY (#167 / #1-02-1)

ISO programming

G1282

Application

Cycle 1282 OCM CIRCLE BOUNDARY allows you to program a circular bounding frame. This cycle can be used to define the outer boundary of an island or a boundary of an open pocket that was programmed before by using the respective OCM standard figure.

Notes

  • This cycle can be executed only in the FUNCTION MODE MILL machining mode.
  • Cycle 1282 is DEF-active, which means that it becomes active as soon as it is defined in the NC program.
  • The boundary data entered in Cycle 1282 are valid for Cycles 1271 to 1274 and 1278.

Cycle parameters

Help graphic

Parameter

Q653 Diameter?

Diameter of the circular bounding frame

Input: 0.001...9999.999

Q654 Position reference for figure?

Specify the position reference for the center:

0: The center of the boundary is referenced to the center of the contour

1: The center of the boundary is referenced to the datum

Input: 0, 1

Q655 Shift in major axis?

Shift of the rectangle boundary along the main axis

Input: -999.999...+999.999

Q656 Shift in minor axis?

Shift of the rectangle boundary along the secondary axis

Input: -999.999...+999.999

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

Example

11 CYCL DEF 1282 OCM CIRCLE BOUNDARY ~

Q653=+50

;DIAMETER ~

Q654=+0

;POSITION REFERENCE ~

Q655=+0

;SHIFT 1 ~

Q656=+0

;SHIFT 2