Departure function DEP LN

Application

With the NC function DEP LN, the control departs from the contour on a straight line perpendicular to the last contour element.

Description of function

The tool moves in a straight line from the last contour point PE to the end point PN.

The distance from the end point PN to the contour point PE is LEN plus the tool radius.

Input

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

11 DEP LN LEN+10 F300

; Depart from the contour on a perpendicular linear path

To navigate to this function:

Insert NC function All functions Path contour Departure functions (DEP) DEP LN

The NC function includes the following syntax elements:

Syntax element

Meaning

DEP LN

Syntax initiator for a linear departure function perpendicular to the contour

LEN

Distance of the auxiliary point PH to the contour

Number or numerical parameter

Optional syntax element

F, FMAX, FZ, FU, FAUTO

Feed rate

Feed rate F

Number or numerical parameter

Optional syntax element

M

M function

Miscellaneous Functions

Number or numerical parameter

Optional syntax element

Example DEP LN

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

11 L Y+20 RR F100

; Approach the last contour element PE with RR

12 DEP LN LEN+20 F100

; Approach PN; distance PE to PN: LEN+20