Rotations with TRANS ROTATION

Application

With the TRANS ROTATION function, you can rotate contours or positions about a rotation angle.

The TRANS ROTATION RESET function allows you to reset the rotation.

Description of function

Rotation is a modal function that is in effect as soon as it has been defined in the NC program.

The control rotates machining in the working plane about the active workpiece datum.

Presets in the machine

The control rotates the input coordinate system (I-CS) as follows:

  • Based on the angle reference axis, i.e. the main axis
  • About the tool axis

Designation of the axes of milling machines

A rotation can be programmed as follows:

  • Absolute, relative to the positive main axis
  • Incremental, relative to the last active rotation

If rotation is active, the control displays it on the TRANS tab of the Status workspace.

The TRANS tab

Input

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

11 TRANS ROTATION ROT+90

; Rotate machining by 90°

To navigate to this function:

Insert NC function All functions Special functions Functions Coordinate transformations TRANS TRANS ROTATION

The NC function includes the following syntax elements:

Syntax element

Meaning

TRANS ROTATION

Syntax initiator for a rotation

ROT or RESET

Enter an absolute or incremental angle of rotation or reset rotation

Number or numerical parameter

Notes

  • This function can be used only in the FUNCTION MODE MILL machining mode.
  • Switching the operating mode with FUNCTION MODE

  • If you execute an absolute rotation with TRANS ROTATION or Cycle 10 ROTATION, then the control overwrites the values of the current rotation. The control adds the incremental values to the values of the current rotation.
  • Cycle 10 ROTATION