Example: Aligning the rotary table from two holes

When aligning a rotary table with cycles14xx, this must be defined by parameters Q1126 ALIGN ROTARY AXIS, Q1120 TRANSFER POSITION and Q1121 CONFIRM ROTATION.

Program sequence

  • Cycle 1411 PROBING TWO CIRCLES
    • Q1126=+2: Position rotary axes with motion control TURN
    • Q1120=+3: Compensation to the mean touch point
    • Q1121=+2: Execute rotary table alignment and accept offset

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

0 BEGIN PGM TOUCHPROBE MM

1 TOOL CALL 600 Z

2 TCH PROBE 1411 PROBING TWO CIRCLES ~

Q1100=+25

;1ST POINT REF AXIS ~

Q1101=+15

;1ST POINT MINOR AXIS ~

Q1102=-10

;1ST POINT TOOL AXIS ~

Q1116=+8

;DIAMETER 1 ~

Q1103=+80

;2ND POINT REF AXIS ~

Q1104=+35

;2ND POINT MINOR AXIS ~

Q1105=-10

;2ND POINT TOOL AXIS ~

Q1117=+8

;DIAMETER 2 ~

Q1115=+0

;GEOMETRY TYPE ~

Q423=+4

;NO. OF PROBE POINTS ~

Q325=+0

;STARTING ANGLE ~

Q1119=+360

;ANGULAR LENGTH ~

Q320=+0

;SET-UP CLEARANCE ~

Q260=+50

;CLEARANCE HEIGHT ~

Q1125=+2

;CLEAR. HEIGHT MODE ~

Q309=+0

;ERROR REACTION ~

Q1126=+2

;ALIGN ROTARY AXIS ~

Q1120=+3

;TRANSFER POSITION ~

Q1121=+2

;CONFIRM ROTATION

3 CALL PGM 35

; Call the part program

4 END PGM TOUCHPROBE MM