Example: Polar hole patterns

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

0 BEGIN PGM 200 MM

1 BLK FORM 0.1 Z X+0 Y+0 Z-40

2 BLK FORM 0.2 X+100 Y+100 Z+0

3 TOOL CALL 200 Z S3500

; Tool call

4 L Z+100 R0 FMAX M3

; Retract the tool

5 CYCL DEF 200 DRILLING ~

Q200=+2

;SET-UP CLEARANCE ~

Q201=-15

;DEPTH ~

Q206=+250

;FEED RATE FOR PLNGNG ~

Q202=+4

;PLUNGING DEPTH ~

Q210=+0

;DWELL TIME AT TOP ~

Q203=+0

;SURFACE COORDINATE ~

Q204=+50

;2ND SET-UP CLEARANCE ~

Q211=+0.25

;DWELL TIME AT DEPTH ~

Q395=+0

;DEPTH REFERENCE

6 CYCL DEF 220 POLAR PATTERN ~

Q216=+30

;CENTER IN 1ST AXIS ~

Q217=+70

;CENTER IN 2ND AXIS ~

Q244=+50

;PITCH CIRCLE DIAMETR ~

Q245=+0

;STARTING ANGLE ~

Q246=+360

;STOPPING ANGLE ~

Q247=+0

;STEPPING ANGLE ~

Q241=+10

;NR OF REPETITIONS ~

Q200=+2

;SET-UP CLEARANCE ~

Q203=+0

;SURFACE COORDINATE ~

Q204=+100

;2ND SET-UP CLEARANCE ~

Q301=+1

;MOVE TO CLEARANCE ~

Q365=+0

;TYPE OF TRAVERSE

7 CYCL DEF 220 POLAR PATTERN ~

Q216=+90

;CENTER IN 1ST AXIS ~

Q217=+25

;CENTER IN 2ND AXIS ~

Q244=+70

;PITCH CIRCLE DIAMETR ~

Q245=+90

;STARTING ANGLE ~

Q246=+360

;STOPPING ANGLE ~

Q247=+30

;STEPPING ANGLE ~

Q241=+5

;NR OF REPETITIONS ~

Q200=+2

;SET-UP CLEARANCE ~

Q203=+0

;SURFACE COORDINATE ~

Q204=+100

;2ND SET-UP CLEARANCE ~

Q301=+1

;MOVE TO CLEARANCE ~

Q365=+0

;TYPE OF TRAVERSE

8 L Z+100 R0 FMAX

; Retract the tool

9 M30

; End of program run

10 END PGM 200 MM