Cycle 402 ROT OF 2 STUDS (#17 / #1-05-1)
ISO programming
G402
Application
Touch probe cycle 402 measures the center points of two cylindrical studs. The control then calculates the angle between the main axis of the working plane and the line connecting the stud center points. With the basic rotation function, the control corrects the calculated value. As an alternative, you can also compensate for the determined misalignment by rotating the rotary table.
Instead of Cycle 402 ROT OF 2 STUDS, HEIDENHAIN recommends using the more powerful Cycle 1411 PROBING TWO CIRCLES.
Related topics
- Cycle 1411 PROBING TWO CIRCLES
Cycle run
- The control positions the touch probe to the pre-position of the first touch point 1, using positioning logic.
- Then the touch probe moves to the entered measuring height 1 and probes four points to find the center of the first stud. The touch probe moves along a circular arc between the touch points, each of which is offset by 90°.
- The touch probe returns to the clearance height and then moves to the touch point 5 of the second stud.
- The control moves the touch probe to the entered measuring height 2 and probes four points to determine the center of the second stud.
- Then the control returns the touch probe to the clearance height and performs the calculated basic rotation.
Notes
- Do not activate the following cycles before the use of touch probe cycles:
- Cycle 7 DATUM SHIFT
- Cycle 8 MIRRORING
- Cycle 10 ROTATION
- Cycle 11 SCALING FACTOR
- Cycle 26 AXIS-SPECIFIC SCALING
- Reset any coordinate transformations beforehand.
- This cycle can be executed only in the FUNCTION MODE MILL machining mode.
- The control will reset an active basic rotation at the beginning of the cycle.
- If you want to compensate for the misalignment by rotating the rotary table, the control will automatically use the following rotary axes:
- C for tool axis Z
- B for tool axis Y
- A for tool axis X
Note on programming
- Before defining this cycle, you must have programmed a tool call to define the touch probe axis.
Cycle parameters
Help graphic | Parameter |
---|---|
Q268 1st stud: center in 1st axis? Center of the first stud in the main axis of the working plane. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q269 1st stud: center in 2nd axis? Center of the first stud in the secondary axis of the working plane. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q313 Diameter of stud 1? Approximate diameter of the first stud. Enter a value that is more likely to be too large than too small. Input: 0...99999.9999 | |
Q261 Meas. height stud 1 in TS axis? Coordinate of the ball tip center (= touch point) in the touch probe axis at which stud 1 will be measured. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q270 2nd stud: center in 1st axis? Center of the second stud in the main axis of the working plane. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q271 2nd stud: center in 2nd axis? Center of the second stud in the secondary axis of the working plane. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q314 Diameter of stud 2? Approximate diameter of the second stud. Enter a value that is more likely to be too large than too small. Input: 0...99999.9999 | |
Q315 Meas. height stud 2 in TS axis? Coordinate of the ball tip center (= touch point) in the touch probe axis at which stud 2 will be measured. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q320 Set-up clearance? Additional distance between touch point and ball tip. Q320 is active in addition to the SET_UP column in the touch probe table. This value has an incremental effect. Input: 0...99999.9999 or PREDEF | |
Q260 Clearance height? Coordinate in the tool axis at which no collision between touch probe and workpiece (fixtures) can occur. This value has an absolute effect. Input: –99999.9999...+99999.9999 or PREDEF | |
Q301 Move to clearance height (0/1)? Define how the touch probe will move between the measuring points: 0: Move to measuring height between measuring points 1: Move to clearance height between measuring points Input: 0, 1 | |
Q307 Preset value for rotation angle If the misalignment is measured relative to any straight line other than the main axis, enter the angle of this reference line. For the basic rotation, the control will then calculate the difference between the value measured and the angle of the reference line. This value has an absolute effect. Input: –360.000...+360.000 | |
Q305 Number in table? Enter the number of a row in the preset table. The control will make the corresponding entry in the following row: Q305 = 0: The rotary axis will be zeroed in row 0 of the preset table. The control will make an entry in the OFFSET column. (Example: For tool axis Z, the entry is made in C_OFFS). In addition, all other values (X, Y, Z, etc.) of the currently active preset will be transferred to row 0 of the preset table. In addition, the control activates the preset from row 0. Q305 > 0: The rotary axis will be zeroed in the preset table row specified here. The control will make an entry in the corresponding OFFSET column of the preset table. (Example: For tool axis Z, the entry is made in C_OFFS). Q305 depends on the following parameters:
Input: 0...99999 | |
Q402 Basic rotation/alignment (0/1) Define whether the control will set the determined misalignment as a basic rotation or will compensate for it by rotating the rotary table: 0: Set basic rotation: The control saves the basic rotation (example: for tool axis Z, the control uses column SPC) 1: Rotate the rotary table: An entry will be made in the corresponding Offset column of the preset table (example: for tool axis Z, the control uses the C_OFFS column); in addition, the corresponding axis will be rotated Input: 0, 1 | |
Q337 Set to zero after alignment? Define whether the control will set the position display of the corresponding rotary axis to 0 after the alignment: 0: The position display is not set to 0 after the alignment 1: After the alignment, the position display is set to 0, provided you have defined Q402 = 1 Input: 0, 1 |
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 TCH PROBE 402 ROT OF 2 STUDS ~ | ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
|