Rotations with TRANS ROTATION
Application
With the TRANS ROTATION function, you can rotate contours or positions about a rotation angle.
The TRANS ROTATION RESET function allows you to reset the rotation.
Related topics
- Cycle 10 ROTATION
Description of function
Rotation is a modal function that is in effect as soon as it has been defined in the NC program.
The control rotates machining in the working plane about the active workpiece datum.
The control rotates the input coordinate system (I-CS) as follows:
- Based on the angle reference axis, i.e. the main axis
- About the tool axis
Designation of the axes of milling machines
A rotation can be programmed as follows:
- Absolute, relative to the positive main axis
- Incremental, relative to the last active rotation
If rotation is active, the control displays it on the TRANS tab of the Status workspace.
Input
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 TRANS ROTATION ROT+90 | ; Rotate machining by 90° |
To navigate to this function:
Insert NC function All functions Special functions Functions Coordinate transformations TRANS TRANS ROTATION
The NC function includes the following syntax elements:
Syntax element | Meaning |
---|---|
TRANS ROTATION | Syntax initiator for a rotation |
ROT or RESET | Enter an absolute or incremental angle of rotation or reset rotation Number or numerical parameter |
Notes
- This function can be used only in the FUNCTION MODE MILL machining mode.
- If you execute an absolute rotation with TRANS ROTATION or Cycle 10 ROTATION, then the control overwrites the values of the current rotation. The control adds the incremental values to the values of the current rotation.