Cycle 247 PRESETTING

ISO programming

G247

Application

Use Cycle 247 PRESETTING to activate a preset defined in the preset table as the new preset.

After cycle definition, all coordinate input and datum shifts (absolute or incremental) reference the new preset.

Status display

In Program Run the control shows the active preset number behind the preset symbol in the Positions workspace.

Notes

  •  
    Notice
    Caution: Significant property damage!
    Undefined fields in the preset table behave differently from fields defined with the value 0: Fields defined with the value 0 overwrite the previous value when activated, whereas with undefined fields the previous value is kept. If the previous value is kept, there is a danger of collision!
    1. Before activating a preset, check whether all columns contain values.
    2. For undefined columns, enter values (e.g., 0)
    3. As an alternative, have the machine manufacturer define 0 as the default value for the columns
  • This cycle can be executed in the FUNCTION MODE MILL machining mode.
  • When activating a preset from the preset table, the control resets the datum shift, mirroring, rotation, scaling factor, and axis-specific scaling factor.
  • If you activate preset number 0 (line 0), then you activate the preset that you last set in the Manual operation operating mode.
  • Cycle 247 is also in effect in the simulation.

Cycle parameters

Help graphic

Parameter

Number for preset?

Enter the number of the desired preset from the preset table. Alternatively, you can use the button with the preset symbol in the action bar to directly select the desired preset from the preset table.

Input: 0...65535

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

Example

11 CYCL DEF 247 PRESETTING ~

Q339=+4

;PRESET NUMBER