Cycle 1010 DRESSING DIAMETER (#156 / #4-04-1)

ISO programming

G1010

Application

 
Machine

Refer to your machine manual.

This function must be enabled and adapted by the machine manufacturer.

Cycle 1010 DRESSING DIAMETER allows you to dress the diameter of your grinding wheel. Depending on the strategy, the control executes movements based on the wheel geometry. If the dressing strategy in Q1016 was set to 1 or 2, the path of the tool to the starting point is not along the grinding wheel, but via a retract path. The control does not apply tool radius compensation in the dressing cycle.

This cycle supports the following grinding wheel edges:

Grinding pin

Special grinding pin

Cup wheel

1, 2, 5, 6

1, 3, 5, 7

not supported

 
Tip

If you work with the dressing roll tool type, then only the grinding pin is permitted.

Dressing of grinding tools

Cycle 1030 ACTIVATE WHEEL EDGE (#156 / #4-04-1)

Notes

 
Notice
Danger of collision!
When you activate FUNCTION DRESS BEGIN, the control switches the kinematics. The grinding wheel becomes the workpiece. The axes may move in the opposite direction. There is a risk of collision during the execution of the function and during the subsequent machining!
  1. Activate the FUNCTION DRESS dressing mode only in the Program Run operating mode or in Single Block mode
  2. Before starting FUNCTION DRESS BEGIN, position the grinding wheel near the dressing tool
  3. Once you have activated FUNCTION DRESS BEGIN, use exclusively cycles from HEIDENHAIN or from your machine manufacturer
  4. In case the NC program is aborted or in case of a power interruption, check the traverse directions of the axes
  5. If necessary, program a kinematic switch-over
 
Notice
Danger of collision!
The dressing cycles position the dressing tool at the programmed grinding wheel edge. Positioning occurs simultaneously in two axes of the working plane. The control does not perform collision checking during this movement! There is a danger of collision!
  1. Before starting FUNCTION DRESS BEGIN, position the grinding wheel near the dressing tool
  2. Make sure there is no risk of collision
  3. Slowly prove-out the NC program
  • You can execute this cycle in the following operating modes: FUNCTION MODE MILL, FUNCTION MODE TURN, FUNCTION MODE GRIND and FUNCTION DRESS.
  • Cycle 1010 is DEF-active.
  • No coordinate transformations are allowed in dressing mode.
  • The control does not graphically depict the dressing operation.
  • If you program a COUNTER FOR DRESSING Q1022, the control executes the dressing procedure only after reaching the defined counter in the tool table. The control saves the DRESS-N-D and DRESS-N-D-ACT counters for every grinding wheel.
  • The cycle supports dressing with a dressing role.
  • This cycle can be run only in dressing mode. The machine manufacturer may already have programmed the switch-over in the cycle sequence.
  • Cycle 1010 DRESSING DIAMETER can be used for dressing a diameter. If the grinding pin has corner radii, dressing would violate the radius shape. To enable dressing a diameter and corner radii, dressing cycle 1015 PROFILE DRESSING must be used.
  • Dressing

Information about dressing with a dressing role

  • For the dressing tool, you must define the dressing role TYPE.
  • For the dressing role, you must define a width: CUTWIDTH. The control takes the width into account during the dressing process.
  • For dressing with a dressing role, only the dressing strategy Q1016=0 is allowed.

Cycle parameters

Help graphic

Parameter

Q1013 Dressing amount?

Value used by the control for the dressing infeed.

Input: 0...9.9999

Q1018 Feed rate for dressing?

Feed rate during the dressing procedure

Input: 0...99999

Q1016 Dressing strategy (0-2)?

Definition of the traversing movement during dressing:

0: Reciprocating; dressing occurs in both directions

1: Pulling: Dressing occurs along the grinding wheel solely towards the active wheel edge.

2: Pushing: Dressing occurs along the grinding wheel solely away from the active wheel edge.

Input: 0, 1, 2

Q1019 Number of dressing infeeds? (optional)

Number of infeeds of the dressing process

Input: 1...999

Q1020 Number of idle strokes? (optional)

Number of times the dressing tool moves along the grinding wheel without removing material after the most recent infeed.

Input: 0...99

Q253 Feed rate for pre-positioning? (optional)

Traversing speed of the tool in mm/min for approach, withdrawal, and retraction movements This input value is optional. If it is not programmed, then FMAX applies.

Input: 0...99999.9999 or FMAX, FAUTO, PREDEF

Q1022 Dressing after number of calls? (optional)

Number of cycle definitions after which the control performs the dressing process. Every cycle definition increments the counter DRESS-N-D-ACT of the grinding wheel in the tool manager.

0: The control dresses the grinding wheel during every cycle definition in the NC program.

>0: The control dresses the grinding wheel after this number of cycle definitions.

Input: 0...99

Q330 Tool number or tool name? (optional)

Number or name of the dressing tool. You can apply the tool directly from the tool table via selection in the action bar.

-1: Dressing tool has been activated prior to the dressing cycle.

Input: –1...99999.9

Q1011 Factor for cutting speed? (optional, depends on the machine manufacturer)

Factor by which the control changes the cutting speed for the dressing tool. The control handles the cutting speed of the grinding wheel.

0: Factor for cutting speed not used

>0: If the value is positive, then the dressing tool turns with the grinding wheel at the point of contact (opposite direction of rotation relative to grinding wheel).

<0: If the value is negative, then the dressing tool turns against the grinding wheel (same direction of rotation of the grinding wheel).

Input: -99.999...99.999

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

Example

11 CYCL DEF 1010 DRESSING DIAMETER ~

Q1013=+0

;DRESSING AMOUNT ~

Q1018=+100

;DRESSING FEED RATE ~

Q1016=+1

;DRESSING STRATEGY ~

Q1019=+1

;NUMBER INFEEDS ~

Q1020=+0

;IDLE STROKES ~

Q253=+1000

;F PRE-POSITIONING ~

Q1022=+0

;COUNTER FOR DRESSING ~

Q330=-1

;TOOL ~

Q1011=+0

;FACTOR VC