Example of a profile program
Grinding wheel edge no. 1
This example program is for dressing a profile of a grinding wheel. The grinding wheel is curved by the amount of a radius on its outer side.
The contour must be closed. The active edge is defined as the datum of the profile. You program the traverse path. (This is the green area in the illustration.)
Data to be used:
- Grinding wheel edge: 1
- Retraction amount: 5 mm
- Width of the pin: 40 mm
- Corner radius: 2 mm
- Depth: 6 mm
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
0 BEGIN PGM 11 MM | |
1 L X-5 Z-5 R0 FMAX | ; Approach starting position |
2 L Z+45 RL FMAX | ; Approach starting position |
3 L X+0 FQ1018 | ; Q1018 = Dressing feed rate |
4 L Z+0 FQ1018 | ; Approach radius edge |
5 RND R2 FQ1018 | ; Rounding |
6 L X+6 FQ1018 | ; Approach final position X |
7 L Z-5 FQ1018 | ; Approach final position Z |
8 L X-5 Z-5 R0 FMAX | ; Approach starting position |
9 END PGM 11 MM |
Grinding wheel edge no. 5
This example program is for dressing a profile of a grinding wheel. The grinding wheel is curved by the amount of a radius on its outer side.
The contour must be closed. The active edge is defined as the datum of the profile. You program the traverse path. (This is the green area in the illustration.)
Data to be used:
- Grinding wheel edge: 5
- Retraction amount: 5 mm
- Width of the pin: 40 mm
- Corner radius: 2 mm
- Depth: 6 mm
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
0 BEGIN PGM 12 MM | |
1 L X+5 Z-5 R0 FMAX | ; Approach starting position |
2 L Z+45 RR FMAX | ; Approach starting position |
3 L X+0 FQ1018 | ; Q1018 = Dressing feed rate |
4 L Z+0 FQ1018 | ; Approach radius edge |
5 RND R2 FQ1018 | ; Rounding |
6 L X-6 FQ1018 | ; Approach final position X |
7 L Z-5 FQ1018 | ; Approach final position Z |
8 L X+5 Z-5 R0 FMAX | ; Approach starting position |
9 END PGM 11 MM |