Example of dressing cycles

This programming example illustrates dressing mode.

The NC program uses the following grinding cycles:

  • Cycle 1030 ACTIVATE WHEEL EDGE
  • Cycle 1010 DRESSING DIAMETER

Program sequence

  • Start milling mode
  • Tool call: Grinding pin
  • Define Cycle 1030 ACTIVATE WHEEL EDGE
  • Tool call: Dressing tool (no mechanical tool change; only a calculated switch-over)
  • Cycle 1010 DRESSING DIAMETER
  • Activate FUNCTION DRESS END

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

Change the following contents as needed:

  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions (e.g., with M91)
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

0 BEGIN PGM DRESS_CYCLE MM

1 BLK FORM 0.1 Z X-9.6 Y-25.1 Z-33

2 BLK FORM 0.2 X+9.6 Y+25.1 Z+1

3 FUNCTION MODE MILL

4 TOOL CALL 501 Z S20000

; Tool call, grinding wheel

5 M140 MB MAX

6 L Z+200 R0 FMAX M3

7 FUNCTION DRESS BEGIN

; Activate dressing procedure

8 CYCL DEF 1030 ACTIVATE WHEEL EDGE ~

Q1006=+5

;WHEEL EDGE

9 TOOL CALL 507

; Tool call, dressing tool

10 L X+5 R0 F2000

11 L Y+0 R0

12 L Z-5 M8

13 CYCL DEF 1010 DRESSING DIAMETER ~

Q1013=+0

;DRESSING AMOUNT ~

Q1018=+300

;DRESSING FEED RATE ~

Q1016=+1

;DRESSING STRATEGY ~

Q1019=+2

;NUMBER INFEEDS ~

Q1020=+3

;IDLE STROKES ~

Q1022=+0

;COUNTER FOR DRESSING ~

Q330=-1

;TOOL ~

Q1011=+0

;FACTOR VC

14 FUNCTION DRESS END

; Deactivate dressing procedure

15 M30

; End of program run

16 END PGM DRESS_CYCLE MM