Cycle 1032 GRINDING WHL LENGTH COMPENSATION (#156 / #4-04-1)
ISO programming
G1032
Application
Refer to your machine manual.
This function must be enabled and adapted by the machine manufacturer.
Use Cycle 1032 GRINDING WHL LENGTH COMPENSATION to define the overall length of a grinding tool. This cycle will modify compensation or basic data, depending on whether an initial dressing operation (INIT_D) was carried out or not. This cycle will insert the values automatically at the correct locations in the tool table.
If initial dressing has not been performed (INIT_D_OK = 0), then you can change the basic data. Basic data affect both grinding and dressing.
If initial dressing has already been carried out (checkbox for INIT_D is enabled), you can edit the compensation data. Compensation data affect grinding only.
Related topics
- Setting up grinding tools
- Cycles for Grinding
Notes
- You can execute this cycle in the following operating modes: FUNCTION MODE MILL, FUNCTION MODE TURN, FUNCTION MODE GRIND and FUNCTION DRESS.
- Cycle 1032 is DEF-active.
Cycle parameters
Help graphic | Parameter |
---|---|
Q1012 Compens. values (0=abs./1=inc.)? Definition of the entered length dimension 0: Entry of the absolute length 1: Entry of the incremental length Input: 0, 1 | |
Q1008 Comp. value outside edge length? Amount by which the tool is corrected lengthwise based on Q1012 or by which the tool data are entered without correction. If Q1012 equals 0, then the absolute length must be entered. If Q1012 equals 1, then the incremental length must be entered. Input: -999.999...+999.999 | |
Q330 Tool number or tool name? Number of name of the grinding tool. Via a selection in the action bar, you have the option of applying the tool directly from the tool table. -1: The active tool from the tool spindle is used. Input: –1...99999.9 |
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Change the following contents as needed:
- Tools
- Cutting parameters
- Feed rates
- Clearance height or safe position
- Machine-specific positions (e.g., with M91)
- Paths of program calls
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 CYCL DEF 1032 GRINDING WHL LENGTH COMPENSATION ~ | ||
| ||
| ||
|