Turning tool table toolturn.trn (#50 / #4-03-1)

Application

The turning tool table toolturn.trn contains the parameters specific to turning tools.

Requirements

  • The Turning (#50 / #4-03-1) or Adv. Spindle Interpol. (#96 / #7-04-1) software option
  • Turning tool is defined in TYP column of tool management
  • Tool types

Description of function

The file name of the turning tool table is toolturn.trn and this table must be stored in the folder TNC:\table.

The values of the parameters ZL, XL and YL go from the tool tip TIP out to the tool-carrier reference point. The algebraic sign of, for example, XL depends on whether the tool tip is to the right or left of the tool spindle. If the tool is oriented and tool tip is to the right of the spindle center, enter a negative value for XL.

For YL the algebraic sign depends on whether the tool tip is in front of or behind the center of the tool spindle. If the tool tip is in front of the spindle center, enter a positive value for YL.

Parameters of the turning tool table toolturn.trn

The toolturn.trn turning tool table provides the following parameters:

Parameter

Meaning

T

Row number in the turning tool table

The tool number allows you to identify each tool unambiguously (e.g., for calling a tool).

Using TOOL CALL to call a tool

You can define an index after the period.

Indexed tool

The row number must match the tool number in the tool.t tool table.

Input: 0.0...32767.9

NAME

Tool name?

The tool name identifies a tool, for example when calling it.

Using TOOL CALL to call a tool

You can define an index after a period (i.e., name.index).

Indexed tool

Input: Text width 32

ZL

Tool length 1?

Length of the tool in the Z direction, with respect to the tool carrier preset

Tool carrier reference point

Input: –99999.9999...+99999.9999

XL

Tool length 2?

Length of the tool in the X direction, with respect to the tool carrier preset

Tool carrier reference point

Input: –99999.9999...+99999.9999

YL

Tool length 3?

Length of the tool in the Y direction, with respect to the tool carrier preset

Tool carrier reference point

Input: –99999.9999...+99999.9999

DZL

Oversize in tool length 1?

Delta value of tool length 1 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Touch-probe cycles for workpieces

Is added to the parameter ZL

Input: –99999.9999...+99999.9999

DXL

Oversize in tool length 2?

Delta value of tool length 2 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Touch-probe cycles for workpieces

Is added to the parameter XL

Input: –99999.9999...+99999.9999

DYL

Tool length oversize 3?

Delta value of tool length 3 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Touch-probe cycles for workpieces

Is added to the parameter YL

Input: –99999.9999...+99999.9999

RS

Cutting edge radius?

The control takes into account the cutter radius for tool tip radius compensation.

Tool radius compensation (TRC) with lathe tools (#50 / #4-03-1)

In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning.

Mill-turning cycles (#50 / #4-03-1)

For the cutter geometry, the control also considers the parameters TO, T-ANGLE, and P-ANGLE.

Input: 0...99999.9999

DRS

Cutter radius oversize?

Delta value of cutter radius as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Touch-probe cycles for workpieces

Is added to the parameter RS

Input: –999.9999...+999.9999

TO

Tool orientation?

From the tool orientation, the control determines the position of the tool tip and, depending on the selected tool type, additional information such as the tool angle direction. This information is necessary, for example, for calculating the cutter radius compensation, milling cutter radius compensation, plunge angle, etc.

Tool radius compensation (TRC) with lathe tools (#50 / #4-03-1)

 
Machine

Refer to your machine manual.

The control displays the tool orientations that are possible for each tool type. The machine manufacturer can change this assignment.

In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning.

Mill-turning cycles (#50 / #4-03-1)

For the cutter geometry, the control also considers the parameters RS, T-ANGLE, and P-ANGLE.

Input: 1...19

ORI

Angle of spindle orientation?

Angle of tool spindle for aligning the turning tool

Input: –360.000...+360.000

SPB-INSERT

Angular offset?

Angular offset for recessing and threading tools, spatial angle B

Input: –90.0...+90.0

P-ANGLE

Point angle

In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning.

Mill-turning cycles (#50 / #4-03-1)

For the cutter geometry, the control also considers the parameters RS, TO, and T-ANGLE.

Input: 0...179.999

T-ANGLE

Tool angle

In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning.

Mill-turning cycles (#50 / #4-03-1)

For the cutter geometry, the control also considers the parameters RS, TO, and P-ANGLE.

Input: 0...179.999

CUTLENGTH

Cutting length of recessing tool

Usable length of the cutting edge of a turning or recessing tool.

The control monitors the usable length of the cutting edge in the turning cycles. If the programmed cutting depth is greater than the usable length of the cutting edge defined in the tool table, then the control will display a warning and will automatically reduce the cutting depth.

Turning cycles

If you do not define CUTWIDTH, the control uses the usable cutting length to define the tool for the graphic representation. The control calculates the missing information from the CUTLENGTH, P-ANGLE and T-ANGLE parameters. If the usable cutting length is less than the actual cutting length, the graphic representation will not match the actual tool.

Input: 0...99999.9999

CUTWIDTH

Width of recessing tool

Cutting width of a turning or recessing tool

The control uses CUTWIDTH for calculations within cycles and to exactly define the tool for the graphic representation.

Mill-turning cycles (#50 / #4-03-1)

Input: 0...99999.9999

DCW

Oversize f. recessing tool width

Delta value of recessing tool width as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Touch-probe cycles for workpieces

Is added to parameter CUTWIDTH

Input: –99999.9999...+99999.9999

TYPE

Type of turning tool

Depending on the selected turning tool type, the control displays the suitable parameters in the Form workspace of the tool management.

Turning tool types (#50 / #4-03-1)

Tool management

Selection by means of a selection window

Input: ROUGH, FINISH, THREAD, RECESS, BUTTON, and RECTURN

WPL-DX-DIAM

Compensation value for the workpiece diameter

Compensation value for the workpiece diameter with respect to the working plane coordinate system (WPL CS).

Working plane coordinate system WPL-CS

Input: –99999.9999...+99999.9999

WPL-DZL

Compensation value for the workpiece length

Compensation value for the workpiece length with respect to the working plane coordinate system (WPL CS).

Working plane coordinate system WPL-CS

Input: –99999.9999...+99999.9999

Notes

  • The control shows delta values from the tool management graphically in the simulation. For delta values from the NC program or from compensation tables, the control changes only the position of the tool in the simulation.
  • Geometry values from the tool table tool.t, such as length L or radius R, are not effective with turning tools.
  • Assign unique tool names!
  • If you define identical tool names for multiple tools, the control will look for the tool in the following sequence:

    • Tool that is in the spindle
    • Tool that is in the magazine
    •  
      Machine

      Refer to your machine manual.

      If there are multiple magazines, the machine manufacturer can specify the search sequence of the tools in the magazines.

    • Tool that is defined in the tool table but is currently not in the magazine
  • If the control, for example, finds multiple available tools in the tool magazine, it inserts the tool with the least remaining tool life.

  • If you want to archive tool tables or use them for simulation, save them with different file names and the corresponding file extension.
  • Use the machine parameter unitOfMeasure (no. 101101) to define inches as the unit of measure. This does not automatically change the unit of measure in the tool table!
  • Creating a tool table in inches

  • The columns WPL-DX-DIAM and WPL-DZL are deactivated in the default configuration.
  • In the machine parameter columnKeys (no. 105501), the machine manufacturer activates the columns WPL-DX-DIAM and WPL-DZL. The names of the columns may be different, however.