磨削循环举例

该示例程序介绍如何用砂轮加工。

NC数控程序使用以下磨削循环:

  • 循环1000 DEFINE RECIP.STROKE
  • 循环1002 STOP RECIP.STROKE
  • 循环1025 GRINDING CONTOUR

程序执行顺序

  • 开始铣削模式
  • 刀具调用:磨针
  • 定义循环1000 DEFINE RECIP.STROKE
  • 定义循环14 CONTOUR GEOMETRY
  • 定义循环1025 GRINDING CONTOUR
  • 定义循环1002 STOP RECIP.STROKE

0 BEGIN PGM GRINDING_CYCLE MM

1 BLK FORM 0.1 Z X-9.6 Y-25.1 Z-33

2 BLK FORM 0.2 X+9.6 Y+25.1 Z+1

3 FUNCTION MODE MILL

4 TOOL CALL 501 Z S20000

; 刀具调用:砂轮

5 L Z+30 R0 FMAX M3

6 CYCL DEF 1000 DEFINE RECIP.STROKE ~

Q1000=+13

;RECIPROCATING STROKE ~

Q1001=+25000

;RECIP. FEED RATE ~

Q1002=+1

;RECIPROCATION TYPE ~

Q1004=+1

;START RECIP. STROKE

7 CYCL DEF 14.0 CONTOUR GEOMETRY

8 CYCL DEF 14.1 CONTOUR LABEL1 /2

9 CYCL DEF 14.2

10 CYCL DEF 1025 GRINDING CONTOUR ~

Q203=+0

;SURFACE COORDINATE ~

Q201=-12

;DEPTH ~

Q14=+0

;ALLOWANCE FOR SIDE ~

Q368=+0.2

;OVERSIZE AT START ~

Q534=+0.05

;LATERAL INFEED ~

Q456=+2

;IDLE STROKES INFEED ~

Q457=+3

;IDLE STROKES AT END ~

Q207=+200

;GRINDING FEED RATE ~

Q253=+750

;F PRE-POSITIONING ~

Q15=+1

;TYPE OF GRINDING ~

Q260=+100

;CLEARANCE HEIGHT ~

Q200=+2

;SET-UP CLEARANCE

11 CYCL CALL

; 循环调用:磨削轮廓

12 L Z+50 R0 FMAX

13 CYCL DEF 1002 STOP RECIP.STROKE ~

Q1005=+1

;CLEAR RECIP. STROKE ~

Q1010=+0

;RECIP.STROKE STOPPOS

14 L Z+250 R0 FMAX

15 L C+0 R0 FMAX M92

16 M30

; 程序结束

17 LBL 1

; 轮廓子程序1

18 L X+3 Y-23 RL

19 L X-3

20 CT X-9 Y-16

21 CT X-7 Y-10

22 CT X-7 Y+10

23 CT X-9 Y+16

24 CT X-3 Y+23

25 L X+3

26 CT X+9 Y+16

27 CT X+7 Y+10

28 CT X+7 Y-10

29 CT X+9 Y-16

30 CT X+3 Y-23

31 LBL 0

32 LBL 2

; 轮廓子程序2

33 L X-25 Y-40 RR

34 L Y+40

35 L X+25

36 L Y-40

37 L X-25

38 LBL 0

39 END PGM GRINDING_CYCLE MM