ISO programming
G221
G221
This cycle enables you to define a point pattern as lines. It can be used for a previously defined machining cycle.
Sequence:
If you run this cycle in Program Run / Single Block mode, the control stops between the individual points of a point pattern.
Help graphic | Parameter |
---|---|
Q225 Starting point in 1st axis? Coordinate of starting point in the main axis of the working plane. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q226 Starting point in 2nd axis? Coordinate of starting point in the secondary axis of the working plane. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q237 Spacing in 1st axis? Spacing between the individual points on a line. This value has an incremental effect. Input: –99999.9999...+99999.9999 | |
Q238 Spacing in 2nd axis? Spacing between the individual lines. This value has an incremental effect. Input: –99999.9999...+99999.9999 | |
Q242 Number of columns? Number of machining operations on a line Input: 0...99999 | |
Q243 Number of lines? Number of lines Input: 0...99999 | |
Q224 Angle of rotation? Angle by which the entire pattern is rotated. The center of rotation lies in the starting point. This value has an absolute effect. Input: –360.000...+360.000 | |
Q200 Set-up clearance? Distance between tool tip and workpiece surface. This value has an incremental effect. Input: 0...99999.9999 or PREDEF | |
Q203 Workpiece surface coordinate? Coordinate on the workpiece surface referenced to the active datum. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q204 2nd set-up clearance? Distance in the tool axis between tool and workpiece (fixtures) at which no collision can occur. This value has an incremental effect. Input: 0...99999.9999 or PREDEF | |
Q301 Move to clearance height (0/1)? Specify how the tool moves between machining processes: 0: Move to the set-up clearance between operations 1: Move to the 2nd set-up clearance between operations Input: 0, 1 |
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 CYCL DEF 221 CARTESIAN PATTERN ~ | ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
12 CYCL CALL |