Tool coordinate system T-CS

Application

In the tool coordinate system T-CS the control implements tool compensations and tool inclinations.

Description of function

Properties of the tool coordinate system T-CS

The tool coordinate system T-CS is a three-dimensional Cartesian coordinate system. Its coordinate origin is the tool tip TIP.

You make entries in the tool management to define the tool tip relative to the tool carrier reference point. The machine manufacturer usually defines the tool carrier reference point on the spindle tip.

Presets in the machine

  • You define the tool tip with the following columns of the tool management relative to the tool carrier reference point:
  • L
  • DL
  • ZL (option 50, option 156)
  • XL (option 50, option 156)
  • YL (option 50, option 156)
  • DZL (option 50, option 156)
  • DXL (option 50, option 156)
  • DYL (option 50, option 156)
  • LO (option 156)
  • DLO (option 156)

Tool carrier reference point

You use positioning blocks in the input coordinate system I-CS to define the position of the tool and therefore the position of the T-CS.

Input coordinate system I-CS

You can use miscellaneous functions to also program in other reference systems, such as M91 for the machine coordinate system M-CS.

Traversing in the machine coordinate system M-CS with M91

The orientation of the T-CS in most cases is identical to that of the I-CS.

T-CS

Use the miscellaneous function M128 to define the tool angle of inclination in the machine coordinate system M-CS using axis angles. The effects of the tool angle of inclination depend on the machine kinematics:

Notes

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

  • Change the following contents as needed:
  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions, e.g. with M91
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

11 L X+10 Y+45 A+10 C+5 R0 M128

; Straight line with miscellaneous function M128 and axis angles

You can also define a tool angle of inclination in the working plane coordinate system WPL-CS, for example with FUNCTION TCPM or a straight line LN.

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

  • Change the following contents as needed:
  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions, e.g. with M91
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

11 FUNCTION TCPM F TCP AXIS SPAT PATHCTRL AXIS

; FUNCTION TCPM with spatial angles

12 L A+0 B+45 C+0 R0 F2500

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

  • Change the following contents as needed:
  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions, e.g. with M91
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

11 LN X+48 Y+102 Z-1.5 NX-0.04658107 NY0.00045007 NZ0.8848844 TX-0.08076201 TY-0.34090025 TZ0.93600126 R0 M128

; Straight line LN with surface normal vector and tool orientation

Transformations in the tool coordinate system T-CS

Position display