ISO programming
G1278
G1278
Use figure cycle 1278 OCM POLYGON to program a polygon. You can use the figure to machine a pocket, an island, or a boundary by face milling. In addition, you can program a tolerance for the reference diameter.
Help graphic | Parameter |
---|---|
Q650 Type of figure? Geometry of the figure: 0: Pocket 1: Island 2: Boundary for face milling Input: 0, 1, 2 | |
Q573 Inscr.circle/circumcircle (0/1)? Define whether the dimension Q571 is referenced to the inscribed circle or the circumcircle: 0: Dimension is referenced to the inscribed circle 1: Dimension is referenced to the circumcircle Input: 0, 1 | |
Q571 Reference circle diameter? Enter the diameter of the reference circle. Specify in parameter Q573 whether the diameter entered here is referenced to the inscribed circle or the circumcircle. You can program a tolerance if needed. Input: 0...99999.9999 | |
Q572 Number of corners? Enter the number of corners of the polygon. The control will always distribute the corners evenly on the polygon. Input: 3...30 | |
Q660 Type of corners? Geometry of the corners: 0: Radius 1: Chamfer Input: 0, 1 | |
Q220 Corner radius? Radius or chamfer of the corner of the figure Input: 0...99999.9999 | |
Q224 Angle of rotation? Angle by which the figure is rotated. The center of rotation is at the center of the figure. This value has an absolute effect. Input: –360.000...+360.000 | |
Q203 Workpiece surface coordinate? Coordinate on the workpiece surface referenced to the active datum. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q201 Depth? Distance between the workpiece surface and the contour floor. This value has an incremental effect. Input: –99999.9999...+0 | |
Q368 Finishing allowance for side? Finishing allowance in the working plane. This value has an incremental effect. Input: 0...99999.9999 | |
Q369 Finishing allowance for floor? Finishing allowance for the floor. This value has an incremental effect. Input: 0...99999.9999 | |
Q260 Clearance height? Coordinate in the tool axis in which no collision with the workpiece can occur (for intermediary positioning and retraction at the end of the cycle). This value has an absolute effect. Input: –99999.9999...+99999.9999 or PREDEF | |
Q578 Radius factor on inside corners? The inside radii of the contour are calculated based on the tool radius plus the product of the tool radius times Q578. Input: 0.05...0.99 |
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 CYCL DEF 1278 OCM POLYGON ~ | ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
|