Cycle 801 RESET ROTARY COORDINATE SYSTEM

ISO programming

G801

Application

 
Machine

Refer to your machine manual.

This function must be enabled and adapted by the machine manufacturer.

The cycle is machine-dependent.

Cycle 801 resets the following settings you have programmed with Cycle 800:

  • Precession angle Q497
  • Reverse tool Q498

If you executed the eccentric turning function with Cycle 800, please note the following: Cycle 800 limits the maximum spindle speed permitted for eccentric turning. It results from a machine-dependent configuration (defined by your machine manufacturer) and the amount of eccentricity. You might have programmed a speed limitation with FUNCTION TURNDATA SMAX before programming Cycle 800. If the value of this speed limitation is smaller than the speed limitation calculated by Cycle 800, the smaller value will be applied. To reset Cycle 800, program Cycle 801. This will also reset the speed limitation set by that cycle. After that, the speed limitation programmed before the cycle call with FUNCTION TURNDATA SMAX takes effect again.

 
Tip

Cycle 801 does not orient the tool to the starting position. If a tool was oriented with Cycle 800, it remains in this position also after resetting.

Notes

  • This cycle can only be executed in the FUNCTION MODE TURN machining mode.
  • With Cycle 801 RESET ROTARY COORDINATE SYSTEM, you can reset the settings you have made with Cycle 800 ADJUST XZ SYSTEM.

Notes on programming

  • To reset Cycle 800, program Cycle 801 RESET ROTARY COORDINATE SYSTEM.
  • Cycle 800 limits the maximum spindle speed permitted for eccentric turning. It results from a machine-dependent configuration (defined by your machine manufacturer) and the amount of eccentricity. You might have programmed a speed limitation with FUNCTION TURNDATA SMAX before programming Cycle 800. If the value of this speed limitation is smaller than the speed limitation calculated by Cycle 800, the smaller value will be applied. To reset Cycle 800, program Cycle 801. This will also reset the speed limitation set by that cycle. After that, the speed limitation programmed before the cycle call with FUNCTION TURNDATA SMAX takes effect again.

Cycle parameters

Help graphic

Parameter

Cycle 801 does not have a cycle parameter. Close cycle input with the END key.