ISO programming
G1434
G1434
Touch probe cycle 1434 determines the center and width of a slot or a ridge using an L-shaped stylus. The control can probe undercuts due to the shape of the stylus. The control probes the two opposing touch points. You can apply the result to the active row of the preset table.
The control orients the touch probe to the calibration angle from the touch probe table.
If, prior to this cycle, you program Cycle 1493 EXTRUSION PROBING, then the control repeats the touch points in the selected direction and at the defined length along a straight line.
Q parameter | Meaning |
---|---|
Q950 to Q952 | Measured center of the slot or ridge in the main axis, auxiliary axis and tool axis |
Q968 | Measured slot or ridge width |
Q980 to Q982 | Measured deviation of the center of the slot or ridge |
Q998 | Measured deviation of the slot width or ridge width |
Q183 |
|
Q970 | If you have programmed Cycle 1493 EXTRUSION PROBING: Maximum deviation based on the center of the slot or the ridge |
Q975 | If you have programmed Cycle 1493 EXTRUSION PROBING: Maximum deviation based on the slot width or ridge width |
Help graphic | Parameter |
---|---|
Q1100 1st noml. position of ref. axis? Absolute nominal position of the center in the main axis of the working plane. Input: –99999.9999...+99999.9999 or enter ?, +, – or @:
| |
Q1101 1st noml. position of minor axis? Absolute nominal position of the center in the secondary axis of the working plane Input: –99999.9999...+9999.9999 Optional input (see Q1100) | |
Q1102 1st nominal position tool axis? Absolute spindle position of the center in the tool axis Input: –99999.9999...+9999.9999 Optional input (see Q1100) | |
Q1113 Width of slot/ridge? Width of the slot or ridge parallel to the secondary axis of the machining plane. This value has an incremental effect. Input: 0...9999.9999 Or – or +: "...-...+...": Evaluation of the tolerance, Evaluation of tolerances | |
Q1115 Geometry type (0/1)? Type of object to be probed: 0: Slot 1: Ridge Input: 0, 1 | |
Q1139 Object plane (1-2)? Plane in which the control interprets the probing direction. 1: YZ plane 2: ZX plane Input: 1, 2 | |
Q1118 Distance of radial approach? Distance to the nominal position at which the touch probe is pre-positioned in the machining plane and to which it retracts after probing. The direction of Q1118 is equivalent to the probing direction and is in the direction opposite to the algebraic sign. This value has an incremental effect. Input: –99999.9999...+9999.9999 | |
Q320 Set-up clearance? Additional distance between touch point and ball tip. Q320 is active in addition to the SET_UP column in the touch probe table. This value has an incremental effect. Input: 0...99999.9999 or PREDEF | |
Q260 Clearance height? Coordinate in the tool axis at which no collision between touch probe and workpiece (fixtures) can occur. This value has an absolute effect. Input: –99999.9999...+99999.9999 or PREDEF | |
Q1125 Traverse to clearance height? Positioning behavior before and after the cycle: –1: Do not move to the clearance height. 0, 1: Move to the clearance height before and after the cycle. Pre-positioning occurs at FMAX_PROBE. Input: -1, 0, +1 | |
Q309 Reaction to tolerance error? Reaction when tolerance is exceeded: 0: Do not interrupt program run when tolerance is exceeded. The control does not open a window with the results. 1: Interrupt program run when tolerance is exceeded. The control opens a window with the results. 2: The control does not open a window if rework is necessary. The control opens a window with results and interrupts the program if the actual position is at scrap level. Input: 0, 1, 2 | |
Q1120 Transfer position? Define which touch point will be used to correct the active preset: 0: No correction 1: Correction of the active preset based on the center of the slot or the ridge. The control corrects the active preset by the amount of the deviation of the nominal and actual position of the center. Input: 0, 1 |
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 TCH PROBE 1434 PROBE SLOT/RIDGE UNDERCUT ~ | ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
|