Cycle 1033 GRINDING WHL RADIUS COMPENSATION (option 156)

ISO programming

G1033

Application

 
Machine

Refer to your machine manual.

This function must be enabled and adapted by the machine manufacturer.

Use Cycle 1033 GRINDING WHL RADIUS COMPENSATION to define the radius of a grinding tool. This cycle will modify compensation or basic data, depending on whether an initial dressing operation (INIT_D) was carried out or not. This cycle will insert the values automatically at the correct locations in the tool table.

If initial dressing has not been performed (INIT_D_OK = 0), then you can change the basic data. Basic data affect both grinding and dressing.

If initial dressing has already been carried out (checkbox for INIT_D is enabled), you can edit the compensation data. Compensation data affect grinding only.

Dressing

Notes

  • This cycle can only be executed in the FUNCTION MODE MILL and FUNCTION MODE TURN machining modes.
  • Cycle 1033 is DEF-active.

Cycle parameters

Help graphic

Parameter

cyc1033_1

Q1012 Compens. values (0=abs./1=inc.)?

Definition of the entered radius dimension

0: Entry of the absolute radius

1: Entry of the incremental radius

Input: 0, 1

Q1007 Compensation value for radius?

Dimension by which the tool radius is compensated for based on Q1012.

If Q1012 equals 0, then the absolute radius must be entered.

If Q1012 equals 1, then the incremental radius must be entered.

Input: –999.9999...+999.9999

Q330 Tool number or tool name?

Number of name of the grinding tool. Via a selection in the action bar, you have the option of applying the tool directly from the tool table.

-1: The active tool from the tool spindle is used.

Input: –1...99999.9

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

  • Change the following contents as needed:
  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions, e.g. with M91
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

Example

11 CYCL DEF 1033 GRINDING WHL RADIUS COMPENSATION ~

Q1012=+1

;INCR. COMPENSATION ~

Q1007=+0

;RADIUS COMPENSATION ~

Q330=-1

;TOOL