ISO programming
G265
G265
With this cycle, you can mill a thread into solid material. In addition, you can choose to machine a counterbore before or after milling the thread.
Countersinking at front
Thread milling
Help graphic | Parameter |
---|---|
Q335 Nominal diameter? Nominal thread diameter Input: 0...99999.9999 | |
Q239 Pitch? Pitch of the thread. The algebraic sign differentiates between right-hand and left-hand threads: += right-hand thread – = left-hand thread Input: –99.9999...+99.9999 | |
Q201 Depth of thread? Distance between workpiece surface and root of thread. This value has an incremental effect. Input: –99999.9999...+99999.9999 | |
Q253 Feed rate for pre-positioning? Traversing speed of the tool in mm/min when plunging or when retracting. Input: 0...99999.9999 or FMAX, FAUTO, PREDEF | |
Q358 Sinking depth at front? Distance between tool point and the top surface of the workpiece for countersinking at the front of the tool. This value has an incremental effect. Input: –99999.9999...+99999.9999 | |
Q359 Countersinking offset at front? Distance by which the control moves the tool center away from the center. This value has an incremental effect. Input: 0...99999.9999 | |
Q360 Countersink (before/after:0/1)? Execution of the chamfer 0 = before thread machining 1 = after thread machining Input: 0, 1 | |
Q200 Set-up clearance? Distance between tool tip and workpiece surface. This value has an incremental effect. Input: 0...99999.9999 or PREDEF | |
Q203 Workpiece surface coordinate? Coordinate on the workpiece surface referenced to the active datum. This value has an absolute effect. Input: –99999.9999...+99999.9999 | |
Q204 2nd set-up clearance? Distance in the tool axis between tool and workpiece (fixtures) at which no collision can occur. This value has an incremental effect. Input: 0...99999.9999 or PREDEF | |
Q254 Feed rate for counterboring? Traversing speed of the tool in mm/min during counterboring Input: 0...99999.999 or FAUTO, FU | |
Q207 Feed rate for milling? Traversing speed of the tool in mm/min while milling Input: 0...99999.999 or FAUTO |
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 CYCL DEF 265 HEL. THREAD DRLG/MLG ~ | ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
12 CYCL CALL |