Turning tool table toolturn.trn (option 50)

Application

The turning tool table toolturn.trn contains the data specific to turning tools.

Requirements

  • Combined milling-turning (software option 50)
  • Turning tool is defined in TYP column of tool management
  • Tool types

Description of function

The file name of the turning tool table is toolturn.trn and this table must be stored in the folder TNC:\table.

The toolturn.trn turning tool table provides the following parameters:

Parameter

Meaning

T

Row number in the turning tool table

The tool number allows identifying each tool unambiguously (e.g., for calling a tool).

Tool call by TOOL CALL

You can define an index after the period.

Indexed tool

The row number must match the tool number in the tool.t tool table.

Input: 0.0...32767.9

NAME

Tool name?

The tool name identifies a tool, for example when calling it.

Tool call by TOOL CALL

You can define an index after the period.

Indexed tool

Input: Text width 32

ZL

ZL

Tool length 1?

Length of the tool in the Z direction, with respect to the tool carrier preset

Tool carrier reference point

Input: –99999.9999...+99999.9999

XL

XL

Tool length 2?

Length of the tool in the X direction, with respect to the tool carrier preset

Tool carrier reference point

Input: –99999.9999...+99999.9999

YL

YL

Tool length 3?

Length of the tool in the Y direction, with respect to the tool carrier preset

Tool carrier reference point

Input: –99999.9999...+99999.9999

DZL

DZL

Oversize in tool length 1?

Delta value of tool length 1 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Programmable Touch Probe Cycles

Is added to the parameter ZL

Input: –99999.9999...+99999.9999

DXL

DXL

Oversize in tool length 2?

Delta value of tool length 2 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Programmable Touch Probe Cycles

Is added to the parameter XL

Input: –99999.9999...+99999.9999

DYL

DYL

Tool length oversize 3?

Delta value of tool length 3 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Programmable Touch Probe Cycles

Is added to the parameter YL

Input: –99999.9999...+99999.9999

RS

RS

Cutting edge radius?

The control takes into account the cutter radius for tool tip radius compensation.

Tooth radius compensation for turning tools (option 50)

In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning.

Cycles for milling and turning

For the cutter geometry, the control also considers the parameters TO, T-ANGLE, and P-ANGLE.

Input: 0...99999.9999

DRS

DRS

Cutter radius oversize?

Delta value of cutter radius as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Programmable Touch Probe Cycles

Is added to the parameter RS

Input: –999.9999...+999.9999

TO

TO

Tool orientation?

From the tool orientation, the control determines the position of the tool tip and, depending on the selected tool type, additional information such as the tool angle direction. This information is necessary, for example, for calculating the cutter radius compensation, milling cutter radius compensation, plunge angle, etc.

Tooth radius compensation for turning tools (option 50)

 
Machine

Refer to your machine manual.

The control displays the tool orientations that are possible for each tool type. The machine manufacturer can change this assignment.

In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning.

Cycles for milling and turning

For the cutter geometry, the control also considers the parameters RS, T-ANGLE, and P-ANGLE.

Input: 1...19

SPB-INSERT

SPBInsert

Angular offset?

Angular offset for recessing tools

Input: –90.0...+90.0

ORI

Ori

Angle of spindle orientation?

Angle of tool spindle for aligning the turning tool

Input: –360.000...+360.000

T-ANGLE

TAngleTurn

Tool angle

In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning.

Cycles for milling and turning

For the cutter geometry, the control also considers the parameters RS, TO, and P-ANGLE.

Input: 0...179.999

P-ANGLE

PAngleTurn

Point angle

In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning.

Cycles for milling and turning

For the cutter geometry, the control also considers the parameters RS, TO, and T-ANGLE.

Input: 0...179.999

CUTLENGTH

Cutlength
CutlengthRe

Cutting length of recessing tool

Length of the cutting edge of a turning or recessing tool

The control monitors the length of the cutting edge in the turning cycles. If the cutting depth programmed in the turning cycle is greater than the length of the cutting edge defined in the tool table, then the control will display a warning and will automatically reduce the cutting depth.

Fundamentals of turning cycles

Input: 0...99999.9999

CUTWIDTH

Cutwidth
CutwidthRe

Width of recessing tool

The control uses the width of a recessing tool for calculations within cycles.

Cycles for milling and turning

Input: 0...99999.9999

DCW

DCW

Oversize f. recessing tool width

Delta value of recessing tool width as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece.

Programmable Touch Probe Cycles

Is added to parameter CUTWIDTH

Input: –99999.9999...+99999.9999

TYPE

Type

Type of turning tool

Depending on the selected turning tool type, the control displays the suitable tool parameters in the Form workspace of tool management.

Types within the turning tools

Tool management

Selection by means of a selection window

Input: ROUGH, FINISH, THREAD, RECESS, BUTTON, and RECTURN

WPL-DX-DIAM

Compensation value for the workpiece diameter

Compensation value for the workpiece diameter with respect to the working plane coordinate system (WPL CS).

Working plane coordinate system WPL-CS

Input: –99999.9999...+99999.9999

WPL-DZL

Compensation value for the workpiece length

Compensation value for the workpiece length with respect to the working plane coordinate system (WPL CS).

Working plane coordinate system WPL-CS

Input: –99999.9999...+99999.9999

Notes

  • The control shows delta values from the tool management graphically in the simulation. For delta values from the NC program or from compensation tables, the control only changes the position of the tool in the simulation.
  • Geometry values from the tool table tool.t, such as length L or radius R, are not effective with turning tools.
  • Assign unique tool names!
  • If you define identical tool names for multiple tools, the control looks for the tool in the following sequence:

    • Tool that is in the spindle
    • Tool that is in the magazine
    •  
      Tip

      Refer to your machine manual.

      If there are multiple magazines, the machine manufacturer can specify the search sequence of the tools in the magazines.

    • Tool that is defined in the tool table but is currently not in the magazine

    If the control, for example, finds multiple available tools in the tool magazine, it inserts the tool with least remaining tool life.

  • If you want to archive tool tables or use them for simulation, save them with different file names and the corresponding file extension.
  • Use the machine parameter unitOfMeasure (no. 101101) to define inches as the unit of measure. This does not automatically change the unit of measure in the tool table!
  • Creating a tool table in inches

  • The columns WPL-DX-DIAM and WPL-DZL are deactivated in the default configuration.
  • In the machine parameter columnKeys (no. 105501), the machine manufacturer activates the columns WPL-DX-DIAM and WPL-DZL. The names of the columns may be different, however.