Example: Shoulder with recess

640_turn_002

NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.

  • Change the following contents as needed:
  • Tools
  • Cutting parameters
  • Feed rates
  • Clearance height or safe position
  • Machine-specific positions, e.g. with M91
  • Paths of program calls

Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.

In addition, test the NC programs using the simulation before the actual program run.

 
Tip

With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.

0 BEGIN PGM 9 MM

1 BLK FORM CYLINDER Z R80 L60

2 TOOL CALL 301

; Tool call

3 M140 MB MAX

; Retract the tool

4 FUNCTION MODE TURN

; Activate turning mode

5 FUNCTION TURNDATA SPIN VCONST:ON VC:150

; Constant cutting speed

6 CYCL DEF 800 ADJUST XZ SYSTEM ~

Q497=+0

;PRECESSION ANGLE ~

Q498=+0

;REVERSE TOOL ~

Q530=+0

;INCLINED MACHINING ~

Q531=+0

;ANGLE OF INCIDENCE ~

Q532=+750

;FEED RATE ~

Q533=+0

;PREFERRED DIRECTION ~

Q535=+3

;ECCENTRIC TURNING ~

Q536=+0

;ECCENTRIC W/O STOP

7 M136

; Feed rate in mm/rev.

8 L X+165 Y+0 R0 FMAX

; Approach starting point in the plane

9 L Z+2 R0 FMAX M304

; Safety clearance, turning spindle on

10 CYCL DEF 812 SHOULDER, LONG. EXT. ~

Q215=+0

;MACHINING OPERATION ~

Q460=+2

;SAFETY CLEARANCE ~

Q491=+160

;DIAMETER AT CONTOUR START ~

Q492=+0

;CONTOUR START IN Z ~

Q493=+150

;DIAMETER AT CONTOUR END ~

Q494=-40

;CONTOUR END IN Z ~

Q495=+0

;ANGLE OF CIRCUM. SURFACE ~

Q501=+1

;TYPE OF STARTING ELEMENT ~

Q502=+2

;SIZE OF STARTING ELEMENT ~

Q500=+1

;RADIUS OF CONTOUR EDGE ~

Q496=+0

;ANGLE OF FACE ~

Q503=+1

;TYPE OF END ELEMENT ~

Q504=+2

;SIZE OF END ELEMENT ~

Q463=+2.5

;MAX. CUTTING DEPTH ~

Q478=+0.25

;ROUGHING FEED RATE ~

Q483=+0.4

;OVERSIZE FOR DIAMETER ~

Q484=+0.2

;OVERSIZE IN Z ~

Q505=+0.2

;FINISHING FEED RATE ~

Q506=+0

;CONTOUR SMOOTHING

11 CYCL CALL

; Cycle call

12 M305

; Turning spindle off

13 TOOL CALL 307

; Tool call

14 M140 MB MAX

; Retract the tool

15 FUNCTION TURNDATA SPIN VCONST:ON VC:100

; Constant cutting speed

16 CYCL DEF 800 ADJUST XZ SYSTEM ~

Q497=+0

;PRECESSION ANGLE ~

Q498=+0

;REVERSE TOOL ~

Q530=+0

;INCLINED MACHINING ~

Q531=+0

;ANGLE OF INCIDENCE ~

Q532=+750

;FEED RATE ~

Q533=+0

;PREFERRED DIRECTION ~

Q535=+0

;ECCENTRIC TURNING ~

Q536=+0

;ECCENTRIC W/O STOP

17 L X+165 Y+0 R0 FMAX

; Approach starting point in the plane

18 L Z+2 R0 FMAX M304

; Safety clearance, turning spindle on

19 CYCL DEF 862 EXPND. RECESS, RADL. ~

Q215=+0

;MACHINING OPERATION ~

Q460=+2

;SAFETY CLEARANCE ~

Q491=+150

;DIAMETER AT CONTOUR START ~

Q492=-12

;CONTOUR START IN Z ~

Q493=+142

;DIAMETER AT CONTOUR END ~

Q494=-18

;CONTOUR END IN Z ~

Q495=+0

;ANGLE OF SIDE ~

Q501=+1

;TYPE OF STARTING ELEMENT ~

Q502=+1

;SIZE OF STARTING ELEMENT ~

Q500=+0

;RADIUS OF CONTOUR EDGE ~

Q496=+0

;ANGLE OF SECOND SIDE ~

Q503=+1

;TYPE OF END ELEMENT ~

Q504=+1

;SIZE OF END ELEMENT ~

Q478=+0.3

;ROUGHING FEED RATE ~

Q483=+0.4

;OVERSIZE FOR DIAMETER ~

Q484=+0.2

;OVERSIZE IN Z ~

Q505=+0.15

;FINISHING FEED RATE ~

Q463=+0

;LIMIT TO DEPTH ~

Q510=+0.8

;RECESSING OVERLAP ~

Q511=+80

;FEED RATE FACTOR ~

Q462=+0

;RETRACTION MODE ~

Q211=+3

;DWELL TIME IN REVS ~

Q562=+1

;MULTIPLE PLUNGING

20 CYCL CALL M8

; Cycle call

21 M305

; Turning spindle off

22 M137

; Feed rate in mm/minute

23 M140 MB MAX

; Retract the tool

24 FUNCTION MODE MILL

; Activate milling mode

25 M30

; End of program

26 END PGM 9 MM