ISO programming
G273
G273
With Cycle 273 OCM FINISHING FLOOR, you can program finishing with the finishing allowance for the floor programmed in Cycle 271.
Positioning logic in OCM cycles
Help graphic | Parameter |
---|---|
Q370 Path overlap factor? Q370 x tool radius = lateral infeed k. The overlap is considered to be the maximum overlap. The overlap can be reduced in order to prevent material from remaining at the corners. Input: 0.0001...1.9999 or PREDEF | |
Q385 Finishing feed rate? Traversing speed of the tool in mm/min for floor finishing Input: 0...99999.999 or FAUTO, FU, FZ | |
Q568 Factor for plunging feed rate? Factor by which the control reduces the feed rate Q385 for downfeed into the material. Input: 0.1...1 | |
Q253 Feed rate for pre-positioning? Traversing speed of the tool in mm/min for approaching the starting position. This feed rate will be used below the coordinate surface, but outside the defined material. Input: 0...99999.9999 or FMAX, FAUTO, PREDEF | |
Q200 Set-up clearance? Distance between lower edge of tool and workpiece surface. This value has an incremental effect. Input: 0...99999.9999 or PREDEF | |
Q438 or QS438 Number/name of rough-out tool? Number or name of the tool that was used by the control to rough out the contour pocket. You can transfer the coarse roughing tool directly from the tool table via the action bar. In addition, you can enter the tool name via the Name in the action bar. The control automatically inserts the closing quotation mark when you exit the input field. –1: The control assumes that the tool last used is the rough-out tool (default behavior). Input: –1...+32767.9 or max. 255 characters | |
Q595 Strategy (0/1)? Machining strategy for finishing 0: Equidistant strategy = constant distances between paths 1: Strategy with constant contact angle Input: 0, 1 | |
Q577 Factor for appr./dept. radius? Factor by which the approach or departure radius will be multiplied. Q577 is multiplied by the tool radius. This results in an approach and departure radius. Input: 0.15...0.99 |
NC programs contained in this User's Manual are suggestions for solutions. The NC programs or individual NC blocks must be adapted before being used on a machine.
Some NC programs depend on the machine kinematics. Adapt these NC programs to your machine kinematics before the first test run.
In addition, test the NC programs using the simulation before the actual program run.
With a program test you determine whether the NC program can be used with the available software options, the active machine kinematics and the current machine configuration.
11 CYCL DEF 273 OCM FINISHING FLOOR ~ | ||
| ||
| ||
| ||
| ||
| ||
| ||
| ||
|