The turning tool table toolturn.trn contains the data specific to turning tools.
Application
Related topics
- Editing tool data in tool management
- Tool data required for turning tools
- Milling-turning operations on the control
- General tool data, regardless of the technology
Tool data for turning tools (option 50)
Requirements
- Combined milling-turning (software option 50)
- Turning tool is defined in TYP column of tool management
Description of function
The file name of the turning tool table is toolturn.trn and this table must be stored in the folder TNC:\table.
The toolturn.trn turning tool table provides the following parameters:
Parameter | Meaning |
---|---|
T | Row number in the turning tool table The tool number allows identifying each tool unambiguously (e.g., for calling a tool). You can define an index after the period. The row number must match the tool number in the tool.t tool table. Input: 0.0...32767.9 |
NAME | Tool name? The tool name identifies a tool, for example when calling it. You can define an index after the period. Input: Text width 32 |
ZL | Tool length 1? Length of the tool in the Z direction, with respect to the tool carrier preset Input: –99999.9999...+99999.9999 |
XL | Tool length 2? Length of the tool in the X direction, with respect to the tool carrier preset Input: –99999.9999...+99999.9999 |
YL | Tool length 3? Length of the tool in the Y direction, with respect to the tool carrier preset Input: –99999.9999...+99999.9999 |
DZL | Oversize in tool length 1? Delta value of tool length 1 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece. Programmable Touch Probe Cycles Is added to the parameter ZL Input: –99999.9999...+99999.9999 |
DXL | Oversize in tool length 2? Delta value of tool length 2 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece. Programmable Touch Probe Cycles Is added to the parameter XL Input: –99999.9999...+99999.9999 |
DYL | Tool length oversize 3? Delta value of tool length 3 as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece. Programmable Touch Probe Cycles Is added to the parameter YL Input: –99999.9999...+99999.9999 |
RS | Cutting edge radius? The control takes into account the cutter radius for tool tip radius compensation. Tooth radius compensation for turning tools (option 50) In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning. Cycles for milling and turning For the cutter geometry, the control also considers the parameters TO, T-ANGLE, and P-ANGLE. Input: 0...99999.9999 |
DRS | Cutter radius oversize? Delta value of cutter radius as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece. Programmable Touch Probe Cycles Is added to the parameter RS Input: –999.9999...+999.9999 |
TO | Tool orientation? From the tool orientation, the control determines the position of the tool tip and, depending on the selected tool type, additional information such as the tool angle direction. This information is necessary, for example, for calculating the cutter radius compensation, milling cutter radius compensation, plunge angle, etc. Tooth radius compensation for turning tools (option 50) Machine Refer to your machine manual. The control displays the tool orientations that are possible for each tool type. The machine manufacturer can change this assignment. In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning. Cycles for milling and turning For the cutter geometry, the control also considers the parameters RS, T-ANGLE, and P-ANGLE. Input: 1...19 |
SPB-INSERT | Angular offset? Angular offset for recessing tools Input: –90.0...+90.0 |
ORI | Angle of spindle orientation? Angle of tool spindle for aligning the turning tool Input: –360.000...+360.000 |
T-ANGLE | Tool angle In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning. Cycles for milling and turning For the cutter geometry, the control also considers the parameters RS, TO, and P-ANGLE. Input: 0...179.999 |
P-ANGLE | Point angle In turning cycles, the control takes into account the cutter geometry to prevent damage to the defined contour. If the contour cannot be machined completely, the control will display a warning. Cycles for milling and turning For the cutter geometry, the control also considers the parameters RS, TO, and T-ANGLE. Input: 0...179.999 |
CUTLENGTH | Cutting length of recessing tool Length of the cutting edge of a turning or recessing tool The control monitors the length of the cutting edge in the turning cycles. If the cutting depth programmed in the turning cycle is greater than the length of the cutting edge defined in the tool table, then the control will display a warning and will automatically reduce the cutting depth. Fundamentals of turning cycles Input: 0...99999.9999 |
CUTWIDTH | Width of recessing tool The control uses the width of a recessing tool for calculations within cycles. Cycles for milling and turning Input: 0...99999.9999 |
DCW | Oversize f. recessing tool width Delta value of recessing tool width as a compensation value in connection with touch probe cycles. The control enters compensation values automatically after measuring the workpiece. Programmable Touch Probe Cycles Is added to parameter CUTWIDTH Input: –99999.9999...+99999.9999 |
TYPE | Type of turning tool Depending on the selected turning tool type, the control displays the suitable tool parameters in the Form workspace of tool management. Types within the turning tools Selection by means of a selection window Input: ROUGH, FINISH, THREAD, RECESS, BUTTON, and RECTURN |
WPL-DX-DIAM | Compensation value for the workpiece diameter Compensation value for the workpiece diameter with respect to the working plane coordinate system (WPL CS). Working plane coordinate system WPL-CS Input: –99999.9999...+99999.9999 |
WPL-DZL | Compensation value for the workpiece length Compensation value for the workpiece length with respect to the working plane coordinate system (WPL CS). Working plane coordinate system WPL-CS Input: –99999.9999...+99999.9999 |
Notes
- The control shows delta values from the tool management graphically in the simulation. For delta values from the NC program or from compensation tables, the control only changes the position of the tool in the simulation.
- Geometry values from the tool table tool.t, such as length L or radius R, are not effective with turning tools.
- Assign unique tool names!
- Tool that is in the spindle
- Tool that is in the magazine
- Tool that is defined in the tool table but is currently not in the magazine
- If you want to archive tool tables or use them for simulation, save them with different file names and the corresponding file extension.
- Use the machine parameter unitOfMeasure (no. 101101) to define inches as the unit of measure. This does not automatically change the unit of measure in the tool table!
- The columns WPL-DX-DIAM and WPL-DZL are deactivated in the default configuration.
If you define identical tool names for multiple tools, the control looks for the tool in the following sequence:
Refer to your machine manual.
If there are multiple magazines, the machine manufacturer can specify the search sequence of the tools in the magazines.
If the control, for example, finds multiple available tools in the tool magazine, it inserts the tool with least remaining tool life.
Creating a tool table in inches
In the machine parameter columnKeys (no. 105501), the machine manufacturer activates the columns WPL-DX-DIAM and WPL-DZL. The names of the columns may be different, however.